Programming Guide 11/2002 Edition - Flint Machine Tools, Inc.

09.01
12.97 General
1 1.5 Cycle support in program editor (SW 5.1 and higher)
Drilling patterns may be repeated if, for example, drilling
and tapping are to be executed in succession. Thus, a
name is assigned to the drilling pattern which will later
be entered in the screen form "Repeat position".
Programming example generated by cycle support
N100 G17 G0 G90 Z20 F2000 S500 M3 Main block
N110 T7 M6 Change drilling machine
N120 G0 G90 X50 Y50 Initial drilling position
N130 MCALL CYCLE82(10,0,2,0,30,5) Modal drilling cycle call
N140 Circle of holes 1: Marker – Name of drilling pattern
N150 HOLES2(50,50,37,20,20,9) Call drilling pattern cycle
N160 ENDLABEL:
N170 MCALL Deselect modal call
N180 T8 M6 Change tap
N190 S400 M3
N200 MCALL
CYCLE84(10,0,2,0,30,,3,5,0.8,180,300,500)
Modal call of tapping cycle
N210 REPEAT Circle of holes 1 Repeat drilling pattern
N220 MCALL Deselect modal call
Moreover, any drilling position
may be entered as repeatable
drilling pattern by means of
screen forms.
Thus, up to five positions may be programmed in the
plane, all values either absolute or incremental
(alternate with "Alternat." soft key). The "Delete all" soft
key creates an empty screen form.
© Siemens AG, 2002. All rights reserved
SINUMERIK 840D/840Di/810D Programming Guide Cycles (PGZ) – 11.02 Edition 1-45
1