CNC 8035 - Programming manual - Fagor Automation

Programming manual
9.
CANNED CYCLES
G69. Z axis roughing canned cycle
CNC 8035
·T· MODEL
(SOFT V16.3X)
·168·
If the parameter "D" is not programmed, the tool withdraws following the profile up to the previous
pass, "C" distance (right figure).
It must be borne in mind that when not programming the parameter D, the cycle execution time is
greater but the finishing stock is smaller.
L±5.5
It defines the finishing stock in X. It is defined in radius and if not programmed, it assumes a value
of "0".
M±5.5
It defines the finishing stock in Z.
If "L" or "M" is programmed with a negative value, the finishing pass is carried out in round corner
mode (G05). When both parameters are programmed with a positive value, the finishing pass is
carried out in square corner mode (G07).
If the parameter "M" is not programmed, the residual stock indicated in the parameter "L" will be
constant throughout the whole profile.
K5.5
It defines the tool feedrate to penetrate the valleys. If not programmed or programmed with a 0 value,
it assumes the machining feedrate (the one programmed before calling the cycle).
F5.5
It defines the feedrate for the last roughing pass. If not programmed or programmed with a 0 value,
it does not run the last roughing pass.
H5.5
It defines the feedrate during the finishing pass. If not programmed or programmed with a 0 value,
it does not run the finishing pass.