EN: man_8065_chn.pdf - Fagor Automation

Execution channels
7.4 G192. Turning speed limit.
Function G192 limits the spindle turning speed in both work modes; G96 and G97. This
function is especially useful when working at constant cutting speed while machining large
parts or when doing spindle maintenance work.
If function G192 is not programmed, the turning speed in each gear is limited by its machine
parameter G00FEED.
Programming the turning speed limit.
The speed limit for all the spindles of the channel may be programmed in the same block.
This function may be programmed while the spindle is running; in this case, the CNC will
limit the speed to the new programmed value.
The turning speed limit is set by programming function G192 and then the maximum speed
for each spindle. The spindle speed is represented by the spindle name followed by the
desired speed. For spindles like S1, S2, etc. the "=" sign must be included between the name
and the speed; the "=" is not necessary for the spindle S.
Programming format.
The programming format is the following; the parameters to be set appear between curly
brackets.
G192 S..S9={vel}
{vel} Maximum spindle speed. The speed is given in rpm.
G192 S1000
G192 S1=334
G192 S150 S2=350
Properties of the function and Influence of the reset, turning the
CNC off and of the M30 function.
Function G192 is modal. Function G192 is canceled on power-up or after an emergency. The
behavior of function G192 after executing an M02 or M30 and after a reset depends on the
setting of machine parameter SPDLSTOP.
SPDLSTOP Behavior of function G192
Yes Functions M02, M30 and reset cancel function G192.
No Functions M02, M30 and reset do not affect the spindle. The CNC maintains
function G192.
7.
MULTI-SPINDLE SYSTEM. SPINDLE CONTROL.
G192. Turning speed limit.
CNC 8065
(REF: 1103)
·123·